Free engineering tool · ISO tolerances

ISO 2768 Tolerance Calculator and ISO 286 Fit Calculator

Use this ISO 2768 tolerance calculator to find the general tolerance for any linear dimension in classes f, m, c and v, then check ISO 286 hole and shaft limits such as H7 tolerance, g6 or p6 and see whether a fit gives clearance, transition or interference.

Values follow ISO 2768-1 and ISO 286-2 for nominal sizes up to 500 mm (ISO 286) and 4,000 mm (ISO 2768-1). Always check the edition named on your drawing.

Tolerance calculator

All fields update the result instantly. Sizes in mm.

ISO 2768-1 general tolerance

–linear tolerance (mm)
Limits
–
Chamfer / radius
–
Angle (shorter side)
–

ISO 286 hole and shaft fit

–fit
Hole limits
–
Shaft limits
–
Clearance (+) / interference (−)
–

Reference values for design and quoting. Machine capability is not finished-part tolerance; achievable limits are confirmed per drawing, material and measurement method.

ISO 2768-1

ISO 2768 general tolerance tables

ISO 2768-1 sets general tolerances for linear and angular dimensions that have no individual tolerance on the drawing. A title block note such as "ISO 2768-m" applies class m to every untoleranced size. Our machining tolerance chart guide explains how these relate to CNC capability.

Linear dimensions (mm)

Nominal size (mm)f – finem – mediumc – coarsev – very coarse
0.5 – 3±0.05±0.1±0.2–
3 – 6±0.05±0.1±0.3±0.5
6 – 30±0.1±0.2±0.5±1
30 – 120±0.15±0.3±0.8±1.5
120 – 400±0.2±0.5±1.2±2.5
400 – 1000±0.3±0.8±2±4
1000 – 2000±0.5±1.2±3±6
2000 – 4000–±2±4±8

For sizes below 0.5 mm, the tolerance must be stated next to the dimension.

External radii and chamfer heights (mm)

Nominal size (mm)fmcv
0.5 – 3±0.2±0.2±0.4±0.4
over 3 – 6±0.5±0.5±1±1
over 6±1±1±2±2

Angular dimensions

Shorter side (mm)fmcv
up to 10±1°±1°±1°30'±3°
over 10 – 50±0°30'±0°30'±1°±2°
over 50 – 120±0°20'±0°20'±0°30'±1°
over 120 – 400±0°10'±0°10'±0°15'±0°30'
over 400±0°5'±0°5'±0°10'±0°20'

ISO 2768-mK combines class m from part 1 with geometric class K from ISO 2768-2. ISO 2768-2 has been withdrawn, so new drawings should state geometric tolerances individually or follow the general specification rules in current ISO GPS standards such as ISO 22081. Standards are available from ISO.

ISO 286

ISO 286 fits and H7 tolerance values

ISO 286 defines tolerance grades (IT) and fundamental deviations (letters) for holes and shafts. The hole-basis system uses an H hole, such as H7, and chooses the shaft letter for the fit. Values below are for a 25 mm nominal size; the calculator covers 0–500 mm. See our slip fit tolerance and bearing press fit tolerance chart guides for applications.

FitHole limitsShaft limitsClearance (+) / interference (−)Typical use
H7/g6+21 / 0 µm-7 / -20 µm+7 to +41 µmClearance: sliding fit, accurate location
H7/h6+21 / 0 µm0 / -13 µm0 to +34 µmClearance: location with small clearance
H8/f7+33 / 0 µm-20 / -41 µm+20 to +74 µmClearance: running fit for shafts
H7/js6+21 / 0 µm+6.5 / -6.5 µm-6.5 to +27.5 µmTransition: easy assembly by hand or mallet
H7/k6+21 / 0 µm+15 / +2 µm-15 to +19 µmTransition: accurate location, light force
H7/n6+21 / 0 µm+28 / +15 µm-28 to +6 µmTransition: tight location, press assembly
H7/p6+21 / 0 µm+35 / +22 µm-35 to -1 µmInterference: light press fit

IT tolerance grades (µm)

Size over – up to (mm)IT5IT6IT7IT8IT9IT10IT11
0 – 3461014254060
3 – 6581218304875
6 – 10691522365890
10 – 1881118274370110
18 – 3091321335284130
30 – 501116253962100160
50 – 801319304674120190
80 – 1201522355487140220
120 – 18018254063100160250
180 – 25020294672115185290
250 – 31523325281130210320
315 – 40025365789140230360
400 – 50027406397155250400

Drawing example

Reading ISO 2768 and ISO 286 on one drawing

  1. The title block says "General tolerances ISO 2768-m".
  2. An untoleranced 25 mm length may vary by ±0.2 mm, an untoleranced 80 mm length by ±0.3 mm.
  3. A bore marked Ø25 H7 has limits 25.000 to 25.021 mm.
  4. The mating pin marked Ø25 g6 has limits 24.980 to 24.993 mm.
  5. The fit gives 0.007 to 0.041 mm clearance: a precise sliding fit.
  6. Critical features still need individual tolerances and an agreed measurement method.

Engineer questions

ISO 2768 and ISO 286 FAQs

What is ISO 2768?

ISO 2768-1 is the standard for general tolerances on linear and angular dimensions without individual tolerances. It has four classes: f (fine), m (medium), c (coarse) and v (very coarse).

What does ISO 2768-mK mean?

Class m for linear and angular dimensions from ISO 2768-1, plus geometric class K from ISO 2768-2. Part 2 has been withdrawn, so check the drawing's standard edition.

What is the ISO 2768-m tolerance for 100 mm?

For a nominal size over 30 up to 120 mm, class m allows ±0.3 mm.

What is an H7 tolerance?

H7 is a hole tolerance with a lower deviation of zero and a width of IT7. For a 25 mm hole it is 0 to +21 µm, so 25.000 to 25.021 mm.

What is the difference between H7/g6 and H7/p6?

H7/g6 always gives a small clearance for sliding or location. H7/p6 always gives interference for a light press fit.

Can CNC machining hold ISO 2768-f?

Usually yes for most sizes, but achievable tolerance depends on the feature, material and measurement method. Critical features should be toleranced individually.

Open multi-cavity injection mold halves on a workbench
Start with what you have

Review Tolerances on Your Drawing

Share your 3D model and 2D drawing, then add the resin, expected demand, receiving machine, critical features and validation needs you already know.

Drawing review for CNC machined parts

Have 3D models or 2D drawings? Email your files to peter@wokemolds.com.

Please review our Privacy Policy before sending project details.