Free engineering tool · ISO tolerances
ISO 2768 Tolerance Calculator and ISO 286 Fit Calculator
Use this ISO 2768 tolerance calculator to find the general tolerance for any linear dimension in classes f, m, c and v, then check ISO 286 hole and shaft limits such as H7 tolerance, g6 or p6 and see whether a fit gives clearance, transition or interference.
Values follow ISO 2768-1 and ISO 286-2 for nominal sizes up to 500 mm (ISO 286) and 4,000 mm (ISO 2768-1). Always check the edition named on your drawing.
Tolerance calculator
All fields update the result instantly. Sizes in mm.
ISO 2768-1 general tolerance
- Limits
- –
- Chamfer / radius
- –
- Angle (shorter side)
- –
ISO 286 hole and shaft fit
- Hole limits
- –
- Shaft limits
- –
- Clearance (+) / interference (−)
- –
Reference values for design and quoting. Machine capability is not finished-part tolerance; achievable limits are confirmed per drawing, material and measurement method.
ISO 2768-1
ISO 2768 general tolerance tables
ISO 2768-1 sets general tolerances for linear and angular dimensions that have no individual tolerance on the drawing. A title block note such as "ISO 2768-m" applies class m to every untoleranced size. Our machining tolerance chart guide explains how these relate to CNC capability.
Linear dimensions (mm)
| Nominal size (mm) | f – fine | m – medium | c – coarse | v – very coarse |
|---|---|---|---|---|
| 0.5 – 3 | ±0.05 | ±0.1 | ±0.2 | – |
| 3 – 6 | ±0.05 | ±0.1 | ±0.3 | ±0.5 |
| 6 – 30 | ±0.1 | ±0.2 | ±0.5 | ±1 |
| 30 – 120 | ±0.15 | ±0.3 | ±0.8 | ±1.5 |
| 120 – 400 | ±0.2 | ±0.5 | ±1.2 | ±2.5 |
| 400 – 1000 | ±0.3 | ±0.8 | ±2 | ±4 |
| 1000 – 2000 | ±0.5 | ±1.2 | ±3 | ±6 |
| 2000 – 4000 | – | ±2 | ±4 | ±8 |
For sizes below 0.5 mm, the tolerance must be stated next to the dimension.
External radii and chamfer heights (mm)
| Nominal size (mm) | f | m | c | v |
|---|---|---|---|---|
| 0.5 – 3 | ±0.2 | ±0.2 | ±0.4 | ±0.4 |
| over 3 – 6 | ±0.5 | ±0.5 | ±1 | ±1 |
| over 6 | ±1 | ±1 | ±2 | ±2 |
Angular dimensions
| Shorter side (mm) | f | m | c | v |
|---|---|---|---|---|
| up to 10 | ±1° | ±1° | ±1°30' | ±3° |
| over 10 – 50 | ±0°30' | ±0°30' | ±1° | ±2° |
| over 50 – 120 | ±0°20' | ±0°20' | ±0°30' | ±1° |
| over 120 – 400 | ±0°10' | ±0°10' | ±0°15' | ±0°30' |
| over 400 | ±0°5' | ±0°5' | ±0°10' | ±0°20' |
ISO 2768-mK combines class m from part 1 with geometric class K from ISO 2768-2. ISO 2768-2 has been withdrawn, so new drawings should state geometric tolerances individually or follow the general specification rules in current ISO GPS standards such as ISO 22081. Standards are available from ISO.
ISO 286
ISO 286 fits and H7 tolerance values
ISO 286 defines tolerance grades (IT) and fundamental deviations (letters) for holes and shafts. The hole-basis system uses an H hole, such as H7, and chooses the shaft letter for the fit. Values below are for a 25 mm nominal size; the calculator covers 0–500 mm. See our slip fit tolerance and bearing press fit tolerance chart guides for applications.
| Fit | Hole limits | Shaft limits | Clearance (+) / interference (−) | Typical use |
|---|---|---|---|---|
| H7/g6 | +21 / 0 µm | -7 / -20 µm | +7 to +41 µm | Clearance: sliding fit, accurate location |
| H7/h6 | +21 / 0 µm | 0 / -13 µm | 0 to +34 µm | Clearance: location with small clearance |
| H8/f7 | +33 / 0 µm | -20 / -41 µm | +20 to +74 µm | Clearance: running fit for shafts |
| H7/js6 | +21 / 0 µm | +6.5 / -6.5 µm | -6.5 to +27.5 µm | Transition: easy assembly by hand or mallet |
| H7/k6 | +21 / 0 µm | +15 / +2 µm | -15 to +19 µm | Transition: accurate location, light force |
| H7/n6 | +21 / 0 µm | +28 / +15 µm | -28 to +6 µm | Transition: tight location, press assembly |
| H7/p6 | +21 / 0 µm | +35 / +22 µm | -35 to -1 µm | Interference: light press fit |
IT tolerance grades (µm)
| Size over – up to (mm) | IT5 | IT6 | IT7 | IT8 | IT9 | IT10 | IT11 |
|---|---|---|---|---|---|---|---|
| 0 – 3 | 4 | 6 | 10 | 14 | 25 | 40 | 60 |
| 3 – 6 | 5 | 8 | 12 | 18 | 30 | 48 | 75 |
| 6 – 10 | 6 | 9 | 15 | 22 | 36 | 58 | 90 |
| 10 – 18 | 8 | 11 | 18 | 27 | 43 | 70 | 110 |
| 18 – 30 | 9 | 13 | 21 | 33 | 52 | 84 | 130 |
| 30 – 50 | 11 | 16 | 25 | 39 | 62 | 100 | 160 |
| 50 – 80 | 13 | 19 | 30 | 46 | 74 | 120 | 190 |
| 80 – 120 | 15 | 22 | 35 | 54 | 87 | 140 | 220 |
| 120 – 180 | 18 | 25 | 40 | 63 | 100 | 160 | 250 |
| 180 – 250 | 20 | 29 | 46 | 72 | 115 | 185 | 290 |
| 250 – 315 | 23 | 32 | 52 | 81 | 130 | 210 | 320 |
| 315 – 400 | 25 | 36 | 57 | 89 | 140 | 230 | 360 |
| 400 – 500 | 27 | 40 | 63 | 97 | 155 | 250 | 400 |
Drawing example
Reading ISO 2768 and ISO 286 on one drawing
- The title block says "General tolerances ISO 2768-m".
- An untoleranced 25 mm length may vary by ±0.2 mm, an untoleranced 80 mm length by ±0.3 mm.
- A bore marked Ø25 H7 has limits 25.000 to 25.021 mm.
- The mating pin marked Ø25 g6 has limits 24.980 to 24.993 mm.
- The fit gives 0.007 to 0.041 mm clearance: a precise sliding fit.
- Critical features still need individual tolerances and an agreed measurement method.
Engineer questions
ISO 2768 and ISO 286 FAQs
What is ISO 2768?
ISO 2768-1 is the standard for general tolerances on linear and angular dimensions without individual tolerances. It has four classes: f (fine), m (medium), c (coarse) and v (very coarse).
What does ISO 2768-mK mean?
Class m for linear and angular dimensions from ISO 2768-1, plus geometric class K from ISO 2768-2. Part 2 has been withdrawn, so check the drawing's standard edition.
What is the ISO 2768-m tolerance for 100 mm?
For a nominal size over 30 up to 120 mm, class m allows ±0.3 mm.
What is an H7 tolerance?
H7 is a hole tolerance with a lower deviation of zero and a width of IT7. For a 25 mm hole it is 0 to +21 µm, so 25.000 to 25.021 mm.
What is the difference between H7/g6 and H7/p6?
H7/g6 always gives a small clearance for sliding or location. H7/p6 always gives interference for a light press fit.
Can CNC machining hold ISO 2768-f?
Usually yes for most sizes, but achievable tolerance depends on the feature, material and measurement method. Critical features should be toleranced individually.
Review Tolerances on Your Drawing
Share your 3D model and 2D drawing, then add the resin, expected demand, receiving machine, critical features and validation needs you already know.
Drawing review for CNC machined parts